Revision control of assys-parts-dfts -previous threads

[andrewsepha]

Just started using SE v19.

I'm a little worried about revision control between drawing types.

For example:-

A300-014-002 (assembly drawing with the issue number at -002)
P300-035-004 (a piece part in the above assembly BOM at revision -004)

The draft drawing would be the same as the piece part model, D300-035-004.

These actual files would be called as per these numbers.

Should I release the above, and then decide to revise P300-035-004, I can go into the assy or model and do my revsion, however when I go to save I'll have to call both the assy file and the piece part a new number i.e. A300-014-003 and P300-035-005 (new revisions -003 and -005). How can I get the draft drawing to up-rev as well?

Also will I still be able to use the older revsion parts (say for an alternative assembly)?


I've asked our SE reseller, however I am still waiting on an answer. Perhaps someone else has encountered the same issue?

Hope I've made myself clear, thanks in advance for you response.

Andrew.

Andrew.

 

[toffeet]

Hello Andrew,

Are you using Revision Manager?

Solid Edge V18 SP6 on WinXP SP2

 

[andrewsepha]

I've had 3 days training and this was not mentioned. Is this inbuilt or an add-on?

 

[toffeet]

Revision Manager is a very important part of SE. Don't ever use Windows Explorer to copy, rename or move a SE file unless there is no other file linked to that specific SE file.

The long way: Click start..All programs...Solid Edge V18..View and Markup. When opening a SE file select the Revision Manager option.

The short way: In Windows Explorer right click the relevant SE file and select "Open with Revision Manager".

You will now see the current document tree of the SE file. Right click the specific part or sub-assembly you want to copy or rename. Select the relevant "Set action to..". Type in the new filename and document number. Click "Perform Actions", top toolbar, 6th from the left.

By using Revision Manager you can be sure that all links will be retained when copying or renaming.

This is what I would have done:

1. Open "A300-014-002" with Revision Manager, right click the top level file, select "Set action to copy" and rename it to "A300-014-003"
2. Right click "P300-035-004" in the same document tree, "Set action to copy" and rename it to "P300-035-005"
3. Click "Perform Actions"
4. Open the draft file of "A300-014-002" with Rev. Man. Right click the top level file in the tree and select "Set action to copy". Rename it to "A300-014-003"
5. Click "Perform Actions"
6. Right click the "A300-014-002".asm file in the same tree and select "Set action to replace". Select the "A300-014-003".asm file.
7. Click "Perform Actions"
8. Repeat the same for the draft file of "P300-035-004"

Solid Edge V18 SP6 on WinXP SP2

 

[toffeet]

Please not that some of the funtions in Revision Manager are only available for when working with a managed library.

Solid Edge V18 SP6 on WinXP SP2

 

[beachcomber]

I would have opened the DRAFT file in Rev Manager and created the new version of that first, by the same method as Toffeet describes. When you open it you will see the Draft file as the top level with the assembly structure attached.
Then create the new assembly revision.
Then create the new part revision.

It's a pity that you aren't using a different character as the delimiter for your revision (eg._002 instead of -002). You could have then used the 'Increment Revision' option.

You MUST get some training on Rev Manager - it's an essential part of Solid Edge if you are not using any other form of PDM or document management system.
I've seen an awful lot of damage done to model structures by incorrect use.

bc

 

[KENAT]

Definitely learn your link management and Revision Manager is a very powerful/usefull tool for this.

I tried teaching myself Rev Manager and had trouble. However I got a colleague to show me copying a file once and then it all came together, the basic functions are pretty simple.

However, I already had a very good understanding of the file linkages. If you don't have this you'll get in trouble.

There are really experienced designers here who just don't get the link management and it causes problems.

 

[andrewsepha]

Thanks to everyone for your help.

Revision manager was briefly mentioned during training, but not explained.

I'll need to do a few trials on test parts before we start messing about with real parts and assemblies, so I may be back with more questions.

-Thanks and regards

Andrew