Flip isometric view 2

[Ralph2]

How can I (SW 2009) flip an isometric view in my drawing to show the other side?
Thanks

 

[JMirisola]

Create the needed view in your model and bring it into the drawing.

Jeff Mirisola
Director of Engineering
M9 Defense
My Blog

 

[cinnamongirl]

The long way:

1- First orient your view so that the side you want to view faces the front (space bar - BACK or whichever side it happens to be).

2- Go to System Options - View.

3- Change Arrow keys to 45°, then hit "OK".

4- Hit the LEFT arrow key once (it'll rotate the view 45 degrees).

5- Repeat step 2 & 3, but instead of 45°, type 35.264°.

6- Hit the DOWN key once.

You can then save the view, hit space bar and click on New View (first icon on the left top).

 

[CorBlimeyLimey]

There are several macros available to create alternative isometric views.

http://sw.fcsuper.com/

---> Make 8 Isometric Views

http://www.lennyworks.com/solidworks/default.asp?ID=20

---> IsoViews

... and the ultimate (24 views) version is attached.

 

[EngineerErrant]

The shortcut/cheating way: create a model view besides the front view (side, bottom, etc.) and create a projected view off it. Projected views at the 45-degree angles to this view will be non-standard isometric views.

"Engineers like to solve problems. If there are no problems handily available, they will create their own problems." -Scott Adams

 

[applejack2]

what I've always done is this:
make drawing from part
drag front view from view pallet
insert projected view top
insert projected view right
insert projected iso (front/top/right)
insert projected view left (left of front view)
insert projected view back (left of left view)
insert projected view iso (back/top/right) (left and up of back view)
delete left and back views
move second iso view next to first iso view

see attached screenshot

 

[cinnamongirl]

One quick solution would be to bring the part/sub-assembly into a new assembly and mate it to the planes to get the desired view.

 

[Ralph2]

Thanks all, you guys / girls are the best. I opted for the Macro that CorBlimeyLimey provided.
All much appreciated

 

[CorBlimeyLimey]

Don't forget to save the part and assy document templates after creating the extra views. Then you won't need to run the macro every time.

 

[fcsuper]

With the 8 isometric views option, I used the macro to save the isometric views in the parts and assemblies templates. Then, forever after, they views are always available on new models!

Matt Lorono, CSWP
Product Definition Specialist, DS SolidWorks Corp
Personal sites:
Lorono's SolidWorks Resources & SolidWorks Legion