fixing non "master model" method drawing

[swale74]

Is there a way to correct a drawing created by a user who didn't understand the master model concept? What I have is part file which contains a large assembly and the user switched to drafting and created a drawing. This file is hard to work with because of the size of the assembly and the drawing. I was hoping I could insert a New parent and then copy the original part file and replacing all the components with the new parent-assembly file? Is this possible. We are running NX 8.0.3.4 native. Thanks in advance.


NX 8.0.3.4 in Windows 7
Mechanical designer

 

[cowski]

File -> Export -> Part...
Create a new file to hold your drawing, then go to drawing selection and choose the sheet(s) that you want in the drawing file. It will ask if you want to add the part as a component of the drawing file, follow the prompts and press OK.

www.nxjournaling.com

 

[jerry1423]

What I would do is firat rename that existing file with the drawing the way you designate a drawing file, usually with the _dwg at the end.

Then I would make the assembly a component of the file with the drawing. You can name it what the drawing was originally named.

go into the model space of the file with the drawing -> Assemblies (pull-down) -> component -> create new component -> enter the name of the model file -> select all the components of the assembly with a rectangle -> make sure both things are toggled on in the menu; Add Defining Objects and Delete Originals -> Ok

You may or may not lose associativity in the drawing, but usually that is not hard to fix.

The parts list will need to set to being based on master model.


This is based on NX7.5 but I don't think it is differnt in NX8.0

 

[NutAce]

What we do here is as follows.

[ol 1]
[li]Create file to hold your Drawing.[/li]
[li]Add the assembly as a component.[/li]
[li]Make component displayed part.[/li]
[li]Select File-Export-Part.[/li]
[li]As destination select your new drawing file.[/li]
[li]Export the drawingsheet from the component.[/li]
[/ol]

Check if all dimensions and text kept their associativity, check if all views were exported.
if Okay you can now remove the "old" sheet from your component.


Ronald van den Broek
Mechanical Engineer
Cad Environment Coordinator
Wärtsilä, Propulsion Services
NX8.5.3 / TC9.1.2
HPZ420 Intel(R) Xeon(R) CPU E5-1620 0 @ 3.60GHz, 32 Gb Win7 64B
Nvidea Quadro4000 2048MB DDR5
HP EliteBook 8570W Intel(R) Core(TM) I7-3740QM CPU @ 2.70GHz, 16Gb Win7 64B

 

[swale74]

This worked thanks for the help!

NX 8.0.3.4 in Windows 7
Mechanical designer